Lesson 11 – Surface Evaluation and Tool Height Correction

What You Will Learn

Inspect a diamond-turned surface using optical metrology
Locate and evaluate the center feature left by the diamond tool
Recognize the difference between a conical and cylindrical center feature
Determine whether the diamond tool is too high or too low
Make a controlled tool-height adjustment and verify the result with another cut

Evaluating the First Surface

After the first cut, the machined surface should be evaluated with optical metrology rather than by appearance alone. A White Light Interferometric (WLI) microscope is well suited to this task because it can measure very small changes in surface height and display the result as a three-dimensional surface map. To evaluate tool centerline height, locate the center of the turned surface by following the spiral cutter marks inward toward the axis of rotation. Once the center is found, measure the size and shape of the remaining center feature. The center feature provides information about whether the diamond cutting edge passed through the spindle centerline at the correct height. Its geometry can therefore be used as diagnostic evidence rather than treated simply as a cosmetic defect.

The Center Feature

As the diamond tool approaches the rotational center of the workpiece, the cutting geometry becomes increasingly sensitive to tool height. If the cutting edge is above or below the spindle centerline, a small residual feature may remain at the center of the machined surface. This feature is often called a center pip. Its diameter, height, and overall shape can provide information about the direction and approximate magnitude of the tool-height error. The goal is not simply to eliminate every visible mark at the center. Instead, the center feature should be measured and interpreted so that any tool-height correction is based on physical evidence.

Conical Versus Cylindrical Shape

For a zero-rake diamond tool, the shape of the center feature can indicate the direction of the tool-height error.

A conical center feature generally indicates that the cutting edge is above the spindle centerline.
A cylindrical or flat-sided center feature generally indicates that the cutting edge is below the spindle centerline.
A three-dimensional WLI surface map can make this distinction easier to see because the slope and height of the feature are displayed directly.

Before adjusting the tool, confirm that the measured feature is located at the true rotational center and is not caused by contamination, a surface defect, debris, or a metrology artifact. If the shape is unclear or inconsistent, repeat the measurement before making a mechanical correction.

Interactive Center-Feature Diagnosis

The interactive center-feature widget shows how optical metrology can be used to evaluate tool height after a diamond-turning cut. Select a conical, minimal, or cylindrical center feature to see how its shape appears in a simulated WLI height map and profile. The widget highlights the spiral turning marks, spindle axis, and residual center feature, then explains what each shape indicates about the diamond tool’s position relative to center. It is designed to help you connect the measured surface geometry with the physical tool-height condition before any machine adjustment is made.

Reading the Center Feature in SPDT

Use the simulated WLI map to identify what the center of a diamond-turned optical surface is telling you about tool height.

Why the center matters: In single-point diamond turning, the surface is generated as the workpiece rotates and the diamond tool feeds across it. Near the exact spindle axis, surface speed approaches zero and the geometry becomes especially sensitive to tool height. A small residual center feature can therefore reveal whether the cutting edge passed through the spindle centerline at the correct vertical position.

Choose the center feature you want to inspect

Simulated White Light Interferometry view

Lower height

Higher height

What you are seeing

Measured shape Conical

Example diameter 28 µm

Tool is above center

For the zero-rake diagnostic convention used in this lesson, the sloped conical feature indicates that the diamond cutting edge is above the spindle centerline.

1. The broad rings are the turned surface

In SPDT, the rotating optic and feeding diamond tool generate a spiral path. As the tool moves inward, those marks converge toward the spindle axis.

2. The colored center region is the height error

The WLI-style color map represents relative surface height. Warm colors indicate higher areas and cool colors lower areas; the exact colors themselves are not material properties.

3. The profile shows the shape more clearly

A sloped peak is easier to recognize in the height profile than in a simple microscope image. That geometry is what makes the center feature diagnostic.

4. The center is unusually sensitive

As radius approaches zero, tangential cutting speed also approaches zero. That makes the final approach to center especially sensitive to tool height, tool geometry, and exact alignment.

Why this matters for precision optics

Localized form error

A residual center feature is a real topographic error on the optical surface. Even though it is small, it can matter when the optic has tight form or wavefront requirements.

Evidence about tool height

The center feature gives the operator physical evidence about whether the diamond passed through the rotational center at the correct vertical position.

Measure before correcting

WLI lets the operator quantify the feature before changing the machine. This supports the SPDT principle of changing one variable at a time and verifying the result.

Training note: The map and micrometer values are illustrative. The conical/high and cylindrical/low interpretation shown here is specifically the zero-rake diagnostic convention used in this lesson. Real acceptance limits and correction magnitudes depend on the machine, tool geometry, workpiece, and qualified process.

Mechanical Tool-Height Adjustment

Tool height is commonly adjusted mechanically at the tool holder. A high-resolution indicator can be placed on a stable, noncutting surface of the tool or holder so that the amount of vertical movement can be measured directly. Before adjustment, the tool-height locking mechanism is loosened carefully while the indicator is observed. The adjustment screw is then used to raise or lower the tool by a controlled amount. Backlash in the adjustment mechanism can affect repeatability. For this reason, the final tool position should be approached from the same direction each time. A common method is to make the final approach by moving the tool upward. If the adjustment overshoots the target and the tool must be moved downward, move it below the desired position and then bring it upward again to the final setting. This reduces the influence of thread clearance and makes the adjustment more repeatable.

Relocking Without Losing the Setting

After the required height correction has been made, the locking mechanism must be tightened while the indicator remains in contact with the tool or holder. Watch the indicator during tightening. Clamping force can cause a small shift in the tool position, and in ultra-precision machining even a very small movement may be significant. The final tool height is therefore the position that exists after the tool is fully secured, not the position measured immediately before tightening. The locking mechanism should be tightened sufficiently to secure the tool without applying unnecessary force. After locking, verify the indicator reading again and confirm that the intended height correction has been maintained.

Recut and Verify

After the tool-height adjustment, the workpiece is recut under controlled conditions. If the workpiece was removed and remounted, the work offset and surface reference should be verified before machining resumes. A rough or semi-finish pass may be used first to re-establish a reliable surface, followed by a light finish pass. The center region is then measured again with WLI. Compare the new center feature with the previous measurement. If the feature becomes smaller and its geometry moves in the expected direction, the correction was effective. If necessary, another small tool-height adjustment can be made. The acceptable center-feature size depends on the part requirements and the qualified machining process. The important principle is the correction sequence:

Measure → Interpret → Adjust → Lock → Recut → Measure Again

Only one controlled variable should be changed at a time. Tool-height correction should be completed before moving on to other coordinate corrections, such as X-offset adjustment, so that each measured result has a clear physical explanation.

Single Point Diamond Turning 1 Section12 Lessons1 Quiz12 Weeks

Curriculum